Drilling below Ø1 mm: speeds, peck cycles and breakage
The ratio that decides feasibility
Depth divided by diameter is the first number to check. A Ø0.5 mm hole 5 mm deep is L/D 10 - achievable with care. The same hole at 15 mm is L/D 30, which is where micro drilling stops being a drilling problem and becomes an EDM or laser problem.
| L/D ratio | Feasibility | What it takes |
|---|---|---|
| Up to 3 | Routine | Standard micro drill, spot drill, one peck per 0.5xD |
| 3-8 | Normal with care | Peck cycle, through-tool or flood coolant, rigid setup |
| 8-15 | Difficult | High-pressure coolant, drill with polished flutes, in-process check |
| 15-25 | Marginal | Specialist micro drilling, peck 0.2xD, frequent retract |
| Above 25 | Change process | EDM hole drilling, laser, or redesign |
Speed and feed, in orders of magnitude
Surface speed for carbide micro drills in aluminium runs 100-200 m/min, which at Ø0.5 mm means 60,000-120,000 rpm - beyond most machining centres. In practice the spindle limit sets the speed and the feed is scaled down to keep chip load per flute at 1-3% of diameter.
| Hole Ø | Typical spindle (rpm) | Feed per flute | Peck depth |
|---|---|---|---|
| Ø0.3 mm | 20,000-30,000 | 0.003-0.006 mm | 0.1 mm (0.3xD) |
| Ø0.5 mm | 15,000-25,000 | 0.005-0.010 mm | 0.15 mm (0.3xD) |
| Ø0.8 mm | 10,000-18,000 | 0.008-0.015 mm | 0.25 mm (0.3xD) |
| Ø1.0 mm | 8,000-15,000 | 0.010-0.020 mm | 0.30 mm (0.3xD) |
| Ø1.5 mm | 6,000-12,000 | 0.015-0.030 mm | 0.50 mm (0.33xD) |
Treat these as starting points, not recipes. Aluminium tolerates more, stainless 316L less - it work-hardens and a rubbing micro drill will fail within a few holes.
Four causes of breakage, in order of frequency
1. Runout
A drill held in an ER collet with 10 μm of runout at the tip is effectively drilling with one flute. At Ø0.5 mm, 10 μm is 2% of the diameter - enough to double the load on one edge. Fix: a dedicated micro collet, checked with a dial indicator at the drill tip, not at the holder.
2. Chips that cannot leave
At Ø0.5 mm the flute volume is tiny. A peck that produces more chip than the flute can hold packs the drill and it snaps on retract. This is why peck depth is expressed as a fraction of diameter, not in millimetres.
3. No coolant at the tip
Flood coolant does not reach the bottom of a 5 mm deep Ø0.5 mm hole. Through-tool coolant does, if the drill and holder support it. Without either, use pecking with full retract and a coolant flush between pecks, and accept a slower cycle.
4. Entry geometry
On a curved or inclined surface, the drill walks before it bites. A spot drill (or a small centre drill) removes that variable. On hard materials, a carbide spot drill with the same included angle as the micro drill is the usual choice.
When to change process
EDM hole drilling (hole popper) handles Ø0.3-3 mm at L/D up to 100, in any conductive material, at the cost of a slower cycle and a recast layer on the wall. Laser drilling is faster but produces taper and a heat-affected zone. The decision rule: if L/D is above 15, or the material is above 45 HRC, or the hole is in a curved surface with a difficult entry, EDM is usually cheaper than the scrap from broken micro drills.
Verification
Ø0.5 mm holes are checked with pin gauges (if the tolerance allows) or with a vision system / toolmaker's microscope. A CMM with a 0.5 mm stylus can measure position but not diameter reliably. If the hole is a flow restrictor, the functional test is airflow - which is often the requirement that actually matters.
Entry on curved and inclined surfaces
A micro drill entering a cylinder or a slope contacts the surface on one edge first. The edge grabs, the drill deflects, and the hole starts a few hundredths off position - or the drill snaps at the tip. Three ways to control it:
- Spot with a centre drill of the same or a steeper included angle, at low feed, deep enough to create a full conical seat.
- Mill a small flat first, when the drawing allows it. A 1 mm flat removes the entry angle entirely.
- Reduce the first peck to 0.1xD and retract fully, so the tip is cleared before the drill commits.
Cost comparison: three routes to a Ø0.6 mm hole
| Route | Cycle per hole | Tool life | Best for |
|---|---|---|---|
| Micro drill, 5 mm deep | 15-25 s | 50-200 holes per drill | Production quantities in aluminium and brass |
| EDM hole drilling | 60-180 s | Electrode wear low | L/D above 15, hardened steel, curved entry |
| Laser drilling | 1-3 s | No tool wear | Thin sections, high volume, taper acceptable |
| Wire EDM (start hole) | n/a | n/a | When the hole is a starting point for a profile |
The comparison that matters is not cycle time per hole - it is cost per good hole. A micro drill that breaks every 80 holes in a part worth 40 yuan is more expensive than a 90-second EDM cycle, even at three times the machine time.
Coolant pressure, in numbers
Through-tool coolant for micro drilling usually needs 30-70 bar to reach the tip and clear chips, depending on hole depth and diameter. A standard flood-coolant machine will not do it, and a high-pressure pump is a different machine specification - not a tooling choice. If a shop quotes micro holes on a machine without through-spindle coolant, the question to ask is how it clears chips on the tenth hole, not the first.
Questions buyers ask
What is the smallest hole a CNC mill can drill?
With a 30,000 rpm spindle and good runout control, Ø0.2 mm is achievable in aluminium at shallow depth. Below that, or at depth, EDM or laser is the practical route.
Why do my Ø0.5 mm drills break on the retract?
Usually packed flutes. The drill cuts fine on the way in, packs chips, and snaps when pulled back. Reduce peck depth and add a full retract with coolant flush.
Can micro holes be drilled in 316L?
Yes, with lower surface speed and a strict peck cycle, but 316L work-hardens: a drill that rubs instead of cutting will fail immediately. Keep the feed up and never let the tool dwell.
How is hole position checked on a 0.5 mm hole?
Vision measurement or a CMM with a small stylus, referenced to the datums on the drawing. Pin gauges check size and passage, not position.
Can a micro hole be drilled without a spot drill?
On a flat surface with a rigid setup, sometimes. On anything curved, inclined or interrupted, spot drilling is cheaper than the scrap from trying without it.
Small-hole work is quoted with the L/D ratio stated up front, so the route is agreed before the first chip.
equipment list